Board File Format

Introduction

This documents the s-expression board file format for all versions of KiCad from 6.0.

  • Printed circuit board files use the .kicad_pcb extension.

This file format was introduced with the launch of KiCad 4.0.
Prior to version 6 of KiCad, strings were only quoted when necessary. Saving an older board file to the latest file format will result in these strings being quoted even though there is no functional change in the board itself.

Layout

A board file includes the following sections:

The section order is not critical other than the header must be the first token. Some sections can may omitted.

Header Section

The kicad_pcb token indicates that it is KiCad board file. This section is required.

Third party scripts should not use pcbnew as the generator identifier. Please use some other identifier so that bugs introduced by third party generators are not confused with the board file created by KiCad. 
(kicad_pcb
  (version VERSION)                                             (1)
  (generator GENERATOR)                                         (2)

  ;; contents of board file...                                  (3)
)
1 The version token attribute defines the board version using the YYYYMMDD date format.
2 The generator token attribute defines the program used to write the file.
3 The remaining sections of the board definition goes here.

General Section

The general token define general information about the board. This section is required.

Most of the redundant information in the general section prior to version 6 has been removed. The removed information does not affect the board output. 
  (general
    (thickness THICKNESS)                                       (1)
  )
1 The thickness token attribute defines the overall board thickness.

Page Section

See the page settings definition in the common s-expression section. This section is required.

Layers Section

The layers token defines all of the layers used by the board. This section is required.

  (layers
    (
      ORDINAL                                                   (1)
      "CANONICAL_NAME"                                          (2)
      TYPE                                                      (3)
      ["USER_NAME"]                                             (4)
    )

    ;; remaining layers...
  )
1 The layer ORDINAL is an integer used to associate the layer stack ordering. This is mostly to ensure correct mapping when the number of layers is increased in the future.
2 The CANONICAL_NAME is the layer name defined for internal board use.
3 The layer TYPE defines the type of layer and can be defined as jumper, mixed, power, signal, or user.
4 The optional USER_NAME attribute defines the custom user name.

Setup Section

The setup token is used to store the current settings such as default item sizes and other options used by the board. This section is required.

  (setup
    [(STACK_UP_SETTINGS)]                                       (1)
    (pad_to_mask_clearance CLEARANCE)                           (2)
    [(solder_mask_min_width MINIMUM_WIDTH)]                     (3)
    [(pad_to_paste_clearance CLEARANCE)]                        (4)
    [(pad_to_paste_clearance_ratio RATIO)]                      (5)
    [(aux_axis_origin X Y)]                                     (6)
    [(grid_origin X Y)]                                         (7)
    (PLOT_SETTINGS)                                             (8)
  )
1 The optional STACK_UP_SETTINGS define the parameters required to manufacture the board.
2 The pad_to_mask_clearance token defines the clearance between footprint pads and the solder mask.
3 The optional solder_mask_min_width defines the minimum solder mask width. If not defined, the minimum width is zero.
4 The optional pad_to_paste_clearance defines the clearance between footprint pads and the solder paste layer. If not defined, the clearance is zero.
5 The optional pad_to_paste_clearance_ratio is the percentage (from 0 to 100) of the footprint pad to make the solder paste. If not defined, the ratio is 100% (the same size as the pad).
6 The optional aux_axis_origin defines the auxiliary origin if it is set to anything other than (0,0).
7 The optional grid_origin defines the grid original if it is set to anything other than (0,0).
8 The PLOT_SETTINGS define how the board was last plotted.

Stack Up Settings

The optional stackup toke defines the board stack up settings and is defined in the setup section.

    (stackup
      (LAYER_STACK_UP_DEFINITIONS)                              (1)
      [(copper_finish "FINISH")]                                (2)
      [(dielectric_constraints yes | no)]                       (3)
      [(edge_connector yes | bevelled)]                         (4)
      [(castellated_pads yes)]                                  (5)
      [(edge_plating yes)]                                      (6)
    )
1 The layer stack up definitions is a list of layer settings for each layer required to manufacture a board including the dielectric material between the actual layers defined in the board editor.
2 The optional copper_finish token is a string that defines the copper finish used to manufacture the board.
3 The optional dielectric_contraints token define if the board should meet all dielectric requirements.
4 The optional edge_connector token defines if the board has an edge connector and if the edge connector is bevelled.
5 The optional castellated_pads token defines if the board edges contain castellated pads.
6 The optional edge_plating token defines if the board edges should be plated.

Stack Up Layer Settings

The layer token defines the stack up setting of a single layer in the board stack up settings.

       (layer
         "NAME" | dielectric                                    (1)
         NUMBER                                                 (2)
         (type "DESCRIPTION")                                   (3)
         [(color "COLOR")]                                      (4)
         [(thickness THICKNESS)]                                (5)
         [(material "MATERIAL")]                                (6)
         [(epsilon_r DIELECTRIC_RESISTANCE)]                    (7)
         [(loss_tangent LOSS_TANGENT)]                          (8)
       )
1 The layer name attribute is either one of the canonical copper or technical layer names listed in the table above or dielectric ID if it is dielectric layer.
2 The layer number attribute defines the stack order of the layer.
3 The layer type token defines a string that describes the layer.
4 The optional layer color token defines a string that describes the layer color. This is only used on solder mask and silkscreen layers.
5 The optional layer thickness token defines the thickness of the layer where appropriate.
6 The optional layer material token defines a string that describes the layer material where appropriate.
7 The optional layer epsilon_r token defines the dielectric constant of the layer material.
8 The optional layer loss_tangent token defines the dielectric loss tangent of the layer

Plot Settings

The pcbplotparams toke defines the plotting and printing settings used for the last plot and is defined in the set up section.

    (pcbplotparams
      (layerselection HEXADECIMAL_BIT_SET)                      (1)
      (disableapertmacros true | false)                         (2)
      (usegerberextensions true | false)                        (3)
      (usegerberattributes true | false)                        (4)
      (usegerberadvancedattributes true | false)                (5)
      (creategerberjobfile true | false)                        (6)
      (svguseinch true | false)                                 (7)
      (svgprecision PRECISION)                                  (8)
      (excludeedgelayer true | false)                           (9)
      (plotframeref true | false)                               (10)
      (viasonmask true | false)                                 (11)
      (mode MODE)                                               (12)
      (useauxorigin true | false)                               (13)
      (hpglpennumber NUMBER)                                    (14)
      (hpglpenspeed SPEED)                                      (15)
      (hpglpendiameter DIAMETER)                                (16)
      (dxfpolygonmode true | false)                             (17)
      (dxfimperialunits true | false)                           (18)
      (dxfusepcbnewfont true | false)                           (19)
      (psnegative true | false)                                 (20)
      (psa4output true | false)                                 (21)
      (plotreference true | false)                              (22)
      (plotvalue true | false)                                  (23)
      (plotinvisibletext true | false)                          (24)
      (sketchpadsonfab true | false)                            (25)
      (subtractmaskfromsilk true | false)                       (26)
      (outputformat FORMAT)                                     (27)
      (mirror true | false)                                     (28)
      (drillshape SHAPE)                                        (29)
      (scaleselection 1)                                        (30)
      (outputdirectory "PATH")                                  (31)
    )
1 The layerselection token defines a hexadecimal bit set of the layers to plot.
2 The disableapertmacros token defines if aperture macros are to be used in gerber plots.
3 The usegerberextensions token defines if the Protel layer file name extensions are to be used in gerber plots.
4 The usegerberattributes token defines if the X2 extensions are used in gerber plots.
5 The usegerberadvancedattributes token defines if the netlist information should be included in gerber plots.
6 The creategerberjobfile token defines if a job file should be created when plotting gerber files.
7 The svguseinch token defines if inch units should be use when plotting SVG files.
8 The svgprecision token defines the units precision used when plotting SVG files.
9 The excludeedgelayer token defines if the board edge layer is plotted on all layers.
10 The plotframeref token defines if the border and title block should be plotted.
11 The viasonmask token defines if the vias are to be tented.
12 The mode token defines the plot mode. An attribute of 1 plots in the normal mode and an attribute of 2 plots in the outline (sketch) mode.
13 The useauxorigin token determines if all coordinates are offset by the defined user origin.
14 The hpglpennumber token defines the integer pen number used for HPGL plots.
15 The hpglpenspeed token defines the integer pen speed used for HPGL plots.
16 The hpglpendiameter token defines the floating point pen size for HPGL plots.
17 The dxfpolygonmode token defines if the polygon mode should be used for DXF plots.
18 The dxfimperialunits token defines if imperial units should be used for DXF plots.
19 The dxfusepcbnewfont token defines if the Pcbnew font (vector font) or the default font should be used for DXF plots.
20 The psnegative token defines if the output should be the negative for PostScript plots.
21 The psa4output token defines if the A4 page size should be used for PostScript plots.
22 The plotreference token defines if hidden reference field text should be plotted.
23 The plotvalue token defines if hidden value field text should be plotted.
24 The plotinvisibletext token defines if hidden text other than the reference and value fields should be plotted.
25 The sketchpadsonfab token defines if pads should be plotted in the outline (sketch) mode.
26 The subtractmaskfromsilk toke defines if the solder mask layers should be subtracted from the silk screen layers for gerber plots.
27 The outputformat token defines the last plot type.

  • 0 - gerber

  • 1 - PostScript

  • 2 - SVG

  • 3 - DXF

  • 4 - HPGL

  • 5 - PDF
28 The mirror token defines if the plot should be mirrored.
29 The drillshape token defines the type of drill marks used for drill files.
30 The scaleselection token defines DOCUMENT ME.
31 The outputdirectory token defines the path relative to the current project path where the plot files will be saved.

Property Section

See the properity definition in the s-expression common section. If no properties are defined, this section will not exist.

Nets Section

The net token defines a net for the board. This section is required.

The net class section has been moved out of the board file into the design rules file. 
  (net
    ORDINAL                                                     (1)
    "NET_NAME"                                                  (2)
  )
1 The oridinal attribute is an integer that defines the net order.
2 The net name is a string that defines the name of the net.

Footprint Section

See the footprint in the s-expression board common definitions. This section will not exist if there are no footprints on the board.

Graphic Items Section

See the Graphic Items section in the s-expression board common definitions. This section will not exist if there are no graphics on the board.

Images Section

See the Images section in the s-expression board common definitions. This section will not exist if there are no images on the board.

Tracks Section

This section lists all of segment, via, and arc objects that make up tracks on the board.

Track Segment

The segment token defines a track segment.

  (segment
    (start X Y)                                                 (1)
    (end X Y)                                                   (2)
    (width WIDTH)                                               (3)
    (layer LAYER_DEFINITION)                                    (4)
    [(locked)]                                                  (5)
    (net NET_NUMBER)                                            (6)
    (tstamp UUID)                                               (7)
  )
1 The start token defines the coordinates of the beginning of the line.
2 The end token defines the coordinates of the end of the line.
3 The width token defines the line width.
4 The layer token defines the canonical layer the track segment resides on.
5 The optional locked token defines if the line cannot be edited.
6 The net token defines by the net ordinal number which net in the net section that the segment is part of.
7 The tstamp token defines the unique identifier of the line object.

Track Via

The via token defines a track via.

  (via
    [TYPE]                                                      (1)
    [(locked)]                                                  (2)
    (at X Y)                                                    (3)
    (size DIAMETER)                                             (4)
    (drill DIAMETER)                                            (5)
    (layers LAYER1 LAYER2)                                      (6)
    [(remove_unused_layers)]                                    (7)
    [(keep_end_layers)]                                         (8)
    [(free)]                                                    (9)
    (net NET_NUMBER)                                            (10)
    (tstamp UUID)                                               (11)
  )
1 The optional type attribute specifies the via type. Valid via types are blind and micro. If no type is defined, the via is a through hole type.
2 The optional locked token defines if the line cannot be edited.
3 The at token attributes define the coordinates of the center of the via.
4 The size token attribute defines the diameter of the via annular ring.
5 The drill token attribute defines the drill diameter of the via.
6 The layers token attributes define the canonical layer set the via connects.
7 The optional remove_unused_layers token specifies DOCUMENT ME.
8 The optional keep_end_layers token specifies DOCUMENT ME. This token is only defined when the remove_unused_layers token is defined.
9 The optional free token indicates that the via is free to be moved outside it’s assigned net.
10 The net token attribute defines by net ordinal number which net in the net section that the segment is part of.
11 The tstamp token defines the unique identifier of the line object.

Track Arc

The arc token defines a track arc.

  (arc
    (start X Y)                                                 (1)
    (mid X Y)                                                   (2)
    (end X Y)                                                   (3)
    (width X Y)                                                 (4)
    (layer LAYER_DEFINITION)                                    (5)
    [(locked)]                                                  (6)
    (net NET_NUMBER)                                            (7)
    (tstamp UUID)                                               (8)
  )
1 The start token defines the coordinates of the beginning of the arc.
2 The mid toke defines the coordinates of the mid point of the radius of the arc.
3 The end token defines the coordinates of the end of the arc.
4 The width token defines the line width.
5 The layer token defines the canonical layer the track arc resides on.
6 The optional locked token defines if the line cannot be edited.
7 The net token defines by the net ordinal number which net in the net section that the segment is part of.
8 The tstamp token defines the unique identifier of the line object.

Zones Section

See the zone definition in the s-expression board common definitions. This section will not exist if there are no zones on the board.

Group Section

See the group definition in the s-expression board common definitions. This section will not exist if there are no groups on the board.

Board Example:

(kicad_pcb (version 3) (host pcbnew "(2013-02-20 BZR 3963)-testing")

  (general
    (links 2)
    (no_connects 0)
    (area 57.924999 28.924999 74.075001 42.075001)
    (thickness 1.6)
    (drawings 5)
    (tracks 5)
    (zones 0)
    (modules 2)
    (nets 3)
  )

  (page A4)
  (layers
    (15 top_side.Cu signal)
    (2 Inner2.Cu signal)
    (1 Inner1.Cu signal)
    (0 bottom_side.Cu signal)
    (16 B.Adhes user)
    (17 F.Adhes user)
    (18 B.Paste user)
    (19 F.Paste user)
    (20 B.SilkS user)
    (21 F.SilkS user)
    (22 B.Mask user)
    (23 F.Mask user)
    (24 Dwgs.User user)
    (25 Cmts.User user)
    (26 Eco1.User user)
    (27 Eco2.User user)
    (28 Edge.Cuts user)
  )

  (setup
    (last_trace_width 0.254)
    (trace_clearance 0.254)
    (zone_clearance 0.2)
    (zone_45_only no)
    (trace_min 0.254)
    (segment_width 0.2)
    (edge_width 0.15)
    (via_size 0.889)
    (via_drill 0.635)
    (via_min_size 0.889)
    (via_min_drill 0.508)
    (uvia_size 0.508)
    (uvia_drill 0.127)
    (uvias_allowed no)
    (uvia_min_size 0.508)
    (uvia_min_drill 0.127)
    (pcb_text_width 0.3)
    (pcb_text_size 1.5 1.5)
    (mod_edge_width 0.15)
    (mod_text_size 1.5 1.5)
    (mod_text_width 0.15)
    (pad_size 0.0005 0.0005)
    (pad_drill 0)
    (pad_to_mask_clearance 0.2)
    (aux_axis_origin 0 0)
    (visible_elements 7FFFFFFF)
    (pcbplotparams
      (layerselection 3178497)
      (usegerberextensions true)
      (excludeedgelayer true)
      (linewidth 50000)
      (plotframeref false)
      (viasonmask false)
      (mode 1)
      (useauxorigin false)
      (hpglpennumber 1)
      (hpglpenspeed 20)
      (hpglpendiameter 15)
      (hpglpenoverlay 2)
      (psnegative false)
      (psa4output false)
      (plotreference true)
      (plotvalue true)
      (plotothertext true)
      (plotinvisibletext false)
      (padsonsilk false)
      (subtractmaskfromsilk false)
      (outputformat 1)
      (mirror false)
      (drillshape 1)
      (scaleselection 1)
      (outputdirectory ""))
  )

  (net 0 "")
  (net 1 /SIGNAL)
  (net 2 GND)

  (net_class Default "Ceci est la Netclass par défaut"
    (clearance 0.254)
    (trace_width 0.254)
    (via_dia 0.889)
    (via_drill 0.635)
    (uvia_dia 0.508)
    (uvia_drill 0.127)
    (add_net "")
    (add_net /SIGNAL)
  )

  (net_class POWER ""
    (clearance 0.254)
    (trace_width 0.5)
    (via_dia 1.2)
    (via_drill 0.635)
    (uvia_dia 0.508)
    (uvia_drill 0.127)
    (add_net GND)
  )

  (module R3 (layer top_side.Cu) (tedit 4E4C0E65) (tstamp 5127A136)
    (at 66.04 33.3502)
    (descr "Resitance 3 pas")
    (tags R)
    (path /5127A011)
    (autoplace_cost180 10)
    (fp_text reference R1 (at 0 0.127) (layer F.SilkS) hide
      (effects (font (size 1.397 1.27) (thickness 0.2032)))
    )
    (fp_text value 330K (at 0 0.127) (layer F.SilkS)
      (effects (font (size 1.397 1.27) (thickness 0.2032)))
    )
    (fp_line (start -3.81 0) (end -3.302 0) (layer F.SilkS) (width 0.2032))
    (fp_line (start 3.81 0) (end 3.302 0) (layer F.SilkS) (width 0.2032))
    (fp_line (start 3.302 0) (end 3.302 -1.016) (layer F.SilkS) (width 0.2032))
    (fp_line (start 3.302 -1.016) (end -3.302 -1.016) (layer F.SilkS) (width 0.2032))
    (fp_line (start -3.302 -1.016) (end -3.302 1.016) (layer F.SilkS) (width 0.2032))
    (fp_line (start -3.302 1.016) (end 3.302 1.016) (layer F.SilkS) (width 0.2032))
    (fp_line (start 3.302 1.016) (end 3.302 0) (layer F.SilkS) (width 0.2032))
    (fp_line (start -3.302 -0.508) (end -2.794 -1.016) (layer F.SilkS) (width 0.2032))
    (pad 1 thru_hole circle (at -3.81 0) (size 1.397 1.397) (drill 0.812799)
      (layers *.Cu *.Mask F.SilkS)
      (net 1 /SIGNAL)
    )
    (pad 2 thru_hole circle (at 3.81 0) (size 1.397 1.397) (drill 0.812799)
      (layers *.Cu *.Mask F.SilkS)
      (net 2 GND)
    )
    (model discret/resistor.wrl
      (at (xyz 0 0 0))
      (scale (xyz 0.3 0.3 0.3))
      (rotate (xyz 0 0 0))
    )
  )

  (module CP4 (layer top_side.Cu) (tedit 5127A26C) (tstamp 5127A146)
    (at 66.1416 36.8808)
    (descr "Condensateur polarise")
    (tags CP)
    (path /50FD6D39)
    (fp_text reference C1 (at 0.508 0) (layer F.SilkS)
      (effects (font (size 1.27 1.397) (thickness 0.254)))
    )
    (fp_text value 10uF (at 0.8584 2.1192) (layer F.SilkS) hide
      (effects (font (size 1.27 1.143) (thickness 0.254)))
    )
    (fp_line (start 5.08 0) (end 4.064 0) (layer F.SilkS) (width 0.3048))
    (fp_line (start 4.064 0) (end 4.064 1.016) (layer F.SilkS) (width 0.3048))
    (fp_line (start 4.064 1.016) (end -3.556 1.016) (layer F.SilkS) (width 0.3048))
    (fp_line (start -3.556 1.016) (end -3.556 -1.016) (layer F.SilkS) (width 0.3048))
    (fp_line (start -3.556 -1.016) (end 4.064 -1.016) (layer F.SilkS) (width 0.3048))
    (fp_line (start 4.064 -1.016) (end 4.064 0) (layer F.SilkS) (width 0.3048))
    (fp_line (start -5.08 0) (end -4.064 0) (layer F.SilkS) (width 0.3048))
    (fp_line (start -3.556 0.508) (end -4.064 0.508) (layer F.SilkS) (width 0.3048))
    (fp_line (start -4.064 0.508) (end -4.064 -0.508) (layer F.SilkS) (width 0.3048))
    (fp_line (start -4.064 -0.508) (end -3.556 -0.508) (layer F.SilkS) (width 0.3048))
    (pad 1 thru_hole rect (at -5.08 0) (size 1.397 1.397) (drill 0.812799)
      (layers *.Cu *.Mask F.SilkS)
      (net 1 /SIGNAL)
    )
    (pad 2 thru_hole circle (at 5.08 0) (size 1.397 1.397) (drill 0.812799)
      (layers *.Cu *.Mask F.SilkS)
      (net 2 GND)
    )
    (model discret/c_pol.wrl
      (at (xyz 0 0 0))
      (scale (xyz 0.4 0.4 0.4))
      (rotate (xyz 0 0 0))
    )
  )

  (gr_text TEST (at 62 31) (layer top_side.Cu)
    (effects (font (size 1.5 1.5) (thickness 0.3)))
  )
  (gr_line (start 58 42) (end 58 29) (angle 90) (layer Edge.Cuts) (width 0.15))
  (gr_line (start 74 42) (end 58 42) (angle 90) (layer Edge.Cuts) (width 0.15))
  (gr_line (start 74 29) (end 74 42) (angle 90) (layer Edge.Cuts) (width 0.15))
  (gr_line (start 58 29) (end 74 29) (angle 90) (layer Edge.Cuts) (width 0.15))

  (segment (start 61.0616 36.8808) (end 61.0616 34.5186) (width 0.254) (layer bottom_side.Cu) (net 1))
  (segment (start 61.0616 34.5186) (end 62.23 33.3502) (width 0.254) (layer bottom_side.Cu) (net 1) (tstamp 5127A159))
  (segment (start 69.85 33.3502) (end 70.993 33.3502) (width 0.5) (layer bottom_side.Cu) (net 2))
  (segment (start 71.2216 33.5788) (end 71.2216 36.8808) (width 0.5) (layer bottom_side.Cu) (net 2) (tstamp 5127A156))
  (segment (start 70.993 33.3502) (end 71.2216 33.5788) (width 0.5) (layer bottom_side.Cu) (net 2) (tstamp 5127A155))

  (zone (net 2) (net_name GND) (layer bottom_side.Cu) (tstamp 5127A1B2) (hatch edge 0.508)
    (connect_pads (clearance 0.2))
    (min_thickness 0.1778)
    (fill (arc_segments 16) (thermal_gap 0.254) (thermal_bridge_width 0.4064))
    (polygon
      (pts
        (xy 59 30) (xy 73 30) (xy 73 41) (xy 59 41)
      )
    )
  )
)

Last Modified